Austenitic stainless steel, 304 and 316 included, is drilled badly more often than any other material in a micro shop. The reasons are well understood, and so are the fixes.
Two properties drive everything
Work hardening. Austenitic stainless hardens rapidly under deformation. An edge that rubs instead of cutting raises the hardness at the contact point, and the next revolution has to cut hardened material instead of annealed material.
Low thermal conductivity. Around 16 W/m·K against roughly 50 for carbon steel. Heat does not leave with the chip, so it goes into the edge.
The two combine into one rule: the tool must always be cutting. Every dwell, every spring pass, every hesitation is a work-hardening event.
What that means for parameters
- Feed has a floor. Below about 0.005 mm/rev at 0.5 mm diameter the edge rubs. Raise feed before you raise speed.
- Speed has a ceiling. Start at 40-60 m/min for 304. Free-machining grades such as 303 tolerate more, up to about 120 m/min.
- Never stop in the hole. Program continuous feed, retract fast, do not pause at the bottom.
- Peck at 1 x D. Chips in stainless are stringy and do not break. Through-coolant is worth more here than anywhere else.
- Do not re-cut chips. A retract that drags chips back into the flutes causes chipping.
At 1.0 mm diameter, 60 m/min corresponds to about 19,000 rpm. Most micro spindles stop at 20,000-25,000 rpm, so the spindle sets the achievable cutting speed, not the tool. That is acceptable: run at maximum spindle speed and keep the feed up.
Coating choice
| Coating | Hardness | Service limit | Role in stainless |
|---|---|---|---|
| TiN | 2400-2500 HV | 550-600 °C | General purpose, moderate speed |
| Bronze | 2200-2500 HV | 500-550 °C | Gummy and slightly abrasive grades |
| Uncoated | 1800-2000 HV | edge-limited | Short runs only |
TiN is the default for mixed production. It provides a thermal barrier and lowers friction against steel. Bronze coating suits gummy or abrasive grades.
Neither coating compensates for a feed that is too low.
Point geometry, and the left-hand question
135° is standard for stainless. It shortens the chisel edge, lowers thrust and self-centres, which matters most when the drill enters a turned or previously drilled surface.
The catalogue also contains left-hand series such as HDC636. These are not for reversing an operation to fix a mistake. Left-hand drills are used on automatic lathes and screw machines where the spindle runs in reverse, and for pull-drilling in fixtures where the tool is drawn through the work. If your machine runs clockwise, use the right-hand equivalent.
Series for stainless
| Series | Diameter | Part numbers | Coating |
|---|---|---|---|
| DC426 | 0.04-3.0 mm | 1073 | Black |
| DC836 | 0.1-14.0 mm | 928 | Bronze |
| HDC636 | 0.15-3.72 mm | 997 | TiN, left-hand |
| DC936 | 0.72-17.2 mm | 53 | Bronze, coolant-through |
For a 2.07 mm hole, DC836 covers it with bronze coating and a wide diameter record. For 0.1-3.0 mm at volume, DC426 gives the largest selection.
Coolant delivery
Flood coolant reaches the outside of the drill and the first few millimetres of the hole. Below about 3 x D the edge is working in its own vapour.
Through-tool coolant fixes that, and the catalogue carries coolant-through series such as DC936 from 0.72 mm to 17.2 mm. The alternative is pecking with an air blast and accepting a shorter tool life.
Pressure matters more than flow. A low-pressure flood will not clear a 0.8 mm hole at any volume.
After drilling
If the hole needs a better tolerance or finish, the sequence matters. Drill 0.02-0.05 mm under the reaming size, then ream with a helical reamer such as CM326. Reaming a hole that was already drilled to size removes no material and only polishes the work-hardened layer.
For tapped holes, drill at the tapping size and keep the feed up. A hole drilled with a rubbing edge is hard at the surface, and a tap will struggle in it.
Reading the failure signature
A stainless drill that is rubbing shows a bright, polished wear land on the margin and a built-up edge on the rake face, with no flank wear. That is not wear, it is work hardening in progress. Raise the feed and the symptom disappears.
A drill that is overheating shows discoloration along the margin and a crater behind the edge. Lower the speed and improve coolant delivery.
FAQ
Which tool for a 2.07 mm hole in 316?
Bronze-coated DC836 at 40-50 m/min, feed 0.03-0.05 mm/rev, peck at 1 x D. Spot first if the surface is not flat.
Can I drill stainless without coolant?
Only for holes under 1 x D and at low speed. Beyond that you will work-harden the hole and lose the drill.
Why do my drills fail at breakthrough?
Breakthrough is where the drill loses its centring support. Reduce feed to about 50% for the last 0.2 mm, or support the exit with a sacrificial plate.